When an 0402 resistor has one solder-starved joint, inspect the nearby copper and vias as well as the paste deposit, placement, wetting and reflow conditions. An exposed path to an open via can allow molten solder to enter the barrel, but the nearby via alone does not establish why the joint is deficient.
Compare the affected and unaffected locations, inspect the actual board construction, and agree on a controlled test with the fabricator and assembler. Depending on the result, options can include a mask dam, a different via treatment, a stencil change or a revised reflow process. Verify the chosen combination on representative assemblies.
This investigation focuses on vias near small component pads and thermal vias under exposed pads. For the design and fabrication of filled, plated-over vias within pads, see the via-in-pad guide and VIPPO design guide.
1. Which "Wicking"?
The word covers several different effects. This page is about the first.
| Term in use | What happens | Where it is covered |
|---|---|---|
| Solder drainage (escape) into vias during reflow | Solder leaves an SMD pad for a connected open via or exposed copper | This page |
| Via-in-pad wicking under BGA balls | Same mechanism under a ball, starving the joint or causing voids | Our BGA soldering defects guide |
| Solder climbing a component lead or wire | Solder wets up a lead, away from the joint | Assembly process topic |
| Barrel fill in wave or selective soldering | Desired wicking of solder up a plated through-hole | Through-hole soldering topic |
| Copper wicking along glass fibers in a drilled hole | A fabrication condition in the laminate, unrelated to solder | IPC-6012 microsection item |
2. What Drives Solder Into a Via
Three things combine:
- A continuous wettable path. Exposed, solderable copper can let molten solder spread from the pad toward a via; wetting and process conditions affect the outcome.
- Capillary action. An open plated hole can draw solder into the barrel when solder reaches it and the surfaces and process conditions permit wetting.
- Heat sinking. A via connected to a plane, or a large copper area, can change local temperature and wetting time, which affects which side wets first.
A correctly fabricated mask dam can interrupt an exposed path. Tenting, plugging or filling may reduce access to the hole, but their effectiveness depends on the specified construction, coverage and assembly process. Confirm the actual result rather than assuming that a treatment closes every path.
3. How Much Solder Can a Via Take?
The following is a geometric planning illustration, not a measured loss or a prediction of joint quality. Assume ideal paste transfer, 50% metal by volume in the deposited paste, and cylindrical open through-holes with the stated finished diameters through a 1.6 mm board. Actual paste composition and transfer must be checked for the material and process.
| Pad and print | Solder metal on the pad | Open via capacity | Ratio |
|---|---|---|---|
| Hypothetical 0402 land, 0.5 × 0.6 mm aperture, 0.12 mm stencil | 0.018 mm³ | One 0.25 mm via: 0.079 mm³ | Geometric capacity is about 4.4× the assumed metal volume |
| Hypothetical 0603 land, 0.8 × 0.9 mm aperture, 0.12 mm stencil | 0.043 mm³ | One 0.25 mm via: 0.079 mm³ | Geometric capacity is about 1.8× the assumed metal volume |
| Hypothetical exposed pad, nine 1.5 × 1.5 mm apertures, 0.12 mm stencil | 1.22 mm³ | Nine 0.30 mm vias: 1.02 mm³ | Geometric capacity is about 84% of the assumed metal volume |
The third row assumes an exposed pad large enough for all nine windows and the required spacing; it is not a proposed layout for a particular QFN. Check the package land pattern, via positions and stencil clearances before using any geometry. A full cylindrical hole volume is an upper geometric capacity, not evidence that a hole fills or that this amount leaves the joint. Wetting, via finish, paste transfer, time and temperature affect the actual result. Measure representative deposits and assemblies before changing paste volume.
4. Situations and the Right Fix
| Situation | Risk | Recommended fix |
|---|---|---|
| Via connected to an SMD pad by an exposed trace | Solder may spread toward the via | Assess a mask dam or a revised via location; check the finished board and deposits. |
| Via touching, overlapping or inside a small pad | Paste release, joint formation and solder loss require review | Assess relocation or a specified fill-and-cap structure with the fabricator and assembler. |
| Thermal vias under a QFN or power package exposed pad | Solder loss, voiding and thermal requirements need joint assessment | Compare via dimensions and treatment, paste windows and reflow results against the package requirements. |
| Pad connected to a large exposed copper area | Solder spreading and thermal imbalance are possible | Review mask coverage, pad definition and thermal connection against electrical and thermal requirements. |
| A via with mask on one or both sides | Coverage, openings and trapped material depend on construction | Confirm the treatment and inspect representative boards. |
For a mask dam, derive the needed spacing from the pad and via mask openings, registration allowance and the fabricator's minimum producible web. Confirm that the specified dam is present on the finished board. There is no single spacing in this example that applies to every design.
5. Compare Treatment and Process Options
- Fill and cap: specify the required structure, finished pad condition and inspection with the fabricator. Confirm cost, manufacturability and assembly results for the design.
- Plug, fill or tent: agree on the side, material, coverage and acceptance criteria. Different constructions can affect solder flow, voiding or trapped chemistry; do not assume that a named treatment guarantees a sealed hole.
- Mask dam: check mask expansion, registration and minimum web, then verify the finished dam. The change may require more layout space or fabrication review.
- Stencil design: evaluate paste volume and aperture placement around thermal vias against the component requirements and measured deposits.
- Reflow and materials: review paste instructions, flux activity and the assembly profile with the assembler and paste supplier. Changes require validation on the actual assembly.
TI's QFN and SON PCB Attachment, SLUA271B, section 3.4.1, describes options and tradeoffs for thermal vias in those packages, including a particular untented OSP example and potential voiding with backside treatment. Analog Devices' Soldering Considerations for Exposed-Pad Packages, EE-352, discusses several via treatments and the dependence on board and assembly conditions. Neither source establishes a universal treatment for every product.
6. Diagnosing a Wicking Defect
| Evidence | Investigation and next check |
|---|---|
| Starved joint next to a via | Compare the matching pad, paste deposit and placement; inspect mask and the potential wettable path. |
| Solder visible in a via or on the opposite side | Examine its connection to the affected pad and compare representative boards; the observation alone does not quantify loss from the joint. |
| Low apparent solder coverage or voids beneath an exposed pad on X-ray | Review image method and limits, deposits, via construction and reflow; an image alone does not identify drainage or outgassing as the cause. |
| SPI volume within limits before reflow | Also check deposit position, coverage and measurement capability; review placement, wetting and subsequent processing. |
| Defects associated with large copper areas | Check exposed copper, local heating and wetting alongside the paste and component conditions. |
Where appropriate, a section through a selected via and joint can provide local evidence of solder location. Document the sample location and method, and compare controlled alternatives with the assembler before applying a repair or board revision. A single section does not establish the behavior of every joint.
7. Fabrication and Assembly Checklist
- Identify critical pads and vias, their locations, finished hole sizes, board thickness, surface finish and both-side geometry.
- Specify the required via construction and side; if using IPC-4761 terminology, confirm the applicable revision, construction and acceptance with the fabricator.
- Define mask openings and any required dam, including registration and minimum-web requirements.
- Supply package requirements and paste data, including stencil openings, target deposits and relevant thermal needs.
- Agree on the assembly and inspection plan, including reflow, representative locations, sampling, acceptance and any X-ray or sectioning.
- Record the chosen changes and results so that board, stencil and assembly revisions remain traceable.
HILPCB offers HDI PCBs, multilayer PCBs and SMT assembly; the required construction, review and inspection scope must be confirmed for the quoted project. Send Gerber or ODB++ data, BOM, CPL, assembly drawings, critical locations and inspection requirements with a quote request. For thermal via design considerations, see the thermal via guide.
FAQ
What is solder wicking into a via?
It is solder flowing from a pad toward and into a nearby or in-pad via during reflow when the geometry and wetting conditions permit. It can contribute to a solder-starved joint, but a suspected case requires investigation.
How far should a via be from an SMD pad?
If the design uses a mask dam, determine spacing from the mask openings, registration allowance and fabricator's minimum web. If a dam is not feasible, review via location and treatment with the fabricator and assembler.
Does via tenting stop solder wicking?
Tenting can reduce solder access in a suitable design, but coverage and effectiveness depend on the construction and process. Confirm the treatment, possible voiding and results on representative assemblies; do not assume one- or two-sided tenting always works or fails.
Can I just add more solder paste?
More paste may change the joint and neighboring deposits without resolving the cause. Review measured paste volume and placement, via construction and reflow with the assembler before testing a stencil change.
Are thermal vias under a QFN a wicking problem?
They can be, depending on the exposed-pad geometry, via treatment and process. Evaluate paste windows and via options against the package's electrical and thermal requirements; use agreed inspection and other evidence to validate the result. X-ray alone does not establish the cause or long-term reliability.
